Configurations in IRONCAD

LAST CHECKED:

October 29, 2026

Configurations in IRONCAD
Emil Rindell

Emil Rindell

Jonas Bryntesson

Jonas Bryntesson

Henrik Andersson

Henrik Andersson

PUBLISHED:

2020-01-01

Emil Rindell

Emil Rindell

Jonas Bryntesson

Jonas Bryntesson

Henrik Andersson

Henrik Andersson

2020-01-01

Different positions and visibility in the same file

IRONCAD has something called configurations. This means that assemblies, partners and features in the same 3D file can have different positions and visibility (suppress mode = shown or not shown). For example, configurations can be used to show a assembly in exploded mode, to show different steps for assembly instructions, to show how a solution will look in different predefined modes, different ways to solve a problem by showing and hiding different things in different configurations, or to show a sheet as it looks before and after manufacturing.

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View a single part or assembly

Configurations can also be used to display only an individual part or subassembly, which is then rendered on the drawing. All other parts and subassemblies are then hidden (suppressed) in the 3D scene. This is a viable alternative to exporting the part to an external file. When flattening a sheet metal part (Sheet Metal Unfold), a configuration is automatically created, allowing you to quickly switch between the bent and flat states. Configurations do not support different colors for parts or the ability to use different properties for, e.g., User Name, Part Number, Description, or other Custom Properties.

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configurations ironcad

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Clicking the Configurations button opens a window with settings.

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configurations ironcad

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Active Configuration

Displays the configuration currently active in the 3D scene. By default, the Default configuration is always active and is automatically created with any new 3D scene. The Default configuration cannot be deleted as it is system-defined.

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configurations ironcad

Configurations

A list of configurations present in the open 3D scene. Configurations are displayed alphabetically and cannot be rearranged into a different order.

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ironcad configurations

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Create...

Creates a new configuration via a new window with options for how the configuration should behave.

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configurations ironcad create

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Rename...

Allows you to rename the selected configuration.

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rename configuration ironcad

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The name is entered in a new window. You can rename both active and inactive configurations.

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rename configuration in ironcad

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Delete

Deletes the selected configuration. NOTE! No warning appears when you delete a configuration.

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delete configuration ironcad

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Apply

Activates/switches to the selected configuration.

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apply configurations ironcad

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Configuration Properties

Displays the active settings for the selected configuration. The meanings of the settings are described further down the page.

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ironcad configurations

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Manager Properties

At the bottom is a setting that controls how configurations are handled in externally linked files. With this setting enabled, only changes made in the main configuration will work. We recommend keeping this setting disabled, as it will counteract changes made in the external files. If a change is made in an externally linked sub-assembly and you then switch to the main assembly, the changes will NOT take effect. However, the old settings in the main configuration will now take effect back down to the sub-configuration and then delete what you last did!

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property manager ironcad

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How to create a new configuration

Click the Create... button

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Name the configuration, perhaps Exploded view, My configuration, or something else that describes what the configuration manages.

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name configuration ironcad

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Then select the options that apply to this configuration.

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Properties

There are primarily three settings to choose between.

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new configuration ironcad

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New Parts/Assemblies added within context of other configurations are suppressed in this configuration.

Straight translation: new parts and subsets added in other configurations are automatically suppressed in this configuration. Or simply explained: allows hiding parts and subsets via suppress in this configuration. Things added in other configurations are hidden.

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vacuum track ironcad

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Track suppression for Intellishapes in addition to Parts/Assemblies

Also hide features (Intellishapes such as holes, radii, etc.) in addition to parts and assemblys

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intellishape supression

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When choosing this option, you also receive a warning stating that file size may increase and regeneration times may become more frequent due to shapes (features) being toggled on and off when switching configurations.

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blind position ironcad

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Configuration stores position of Parts/Assemblies

The configuration saves the position of parts and assemblys.

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note configurations ironcad

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Note: If the parameter table is used to control visibility (suppress), these parameters will take precedence over settings controlled via configurations.

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The three most common types of configurations

The three most common configuration variants and their options are as follows:

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Exploded configuration

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exploded view ironcad

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Hide certain objects and make it possible to move other objects apart.

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Assembly instruction

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mounting ironcad

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Hide certain objects and make it possible to move other objects apart. Usually multiple configurations with the same setting, e.g., Position 1, 2, etc.

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Part drawing

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detailed drawing ironcad

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Hide certain objects and everything added in other configurations is automatically hidden in this configuration.

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Advanced Properties

Exploded configuration (for free positional movement)

Used only for 3D files where the parts are positioned with constraints. With this option checked, the anchor point is released and you can freely drag the parts around, even though they are constrained to each other. This is the only way to pull apart constrained objects without destroying or removing the constraints.

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ironcad configurations

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Note: Position and projection locks will not be respected in this configuration, though positions are still saved. This setting automatically propagates down to external links. If you are going to create an exploded configuration, you should primarily use option number three, Configuration stores position of Parts/Assemblies, rather than this one.

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Configurations and external links

It is possible to switch the configuration for linked external files, parts or assemblys. Maybe you want to display a subset in a different predefined mode and since you have already created a configuration in its own file, you can easily access that configuration. By right-clicking on the path directly below the icon for externally linked parts or assemblys, the option to toggle the active configuration is available.

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configuration change ironcad

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In the Scene Browser, expand the part or sub-collection by clicking on the plus sign and then right-clicking on the icon where the path to the external file is displayed. After selecting Change Configuration... this box will appear where you can switch between different modes for the linked subset or part.

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change configurations ironcad

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Choosing which configuration an externally linked part or subset should use will not affect other instances of the same file. So you can use the same file for different projects, but use different configurations in each instance, without affecting the original.

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Sheet metal / Sheet metal

When a sheet metal part is unfolded, a new configuration is automatically created with the unfolded part. This is partly so that you can quickly switch to the unfolded mode without having to wait for a new regeneration of the plate, but more importantly to be able to map the unfolded plate on a 2D drawing. To unfold a plate, right-click on it and select Unfold. This automatically creates a configuration called Unfolded "name of plate".

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sheet unfolded ironcad

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2D Drawing

When creating views in a 2D drawing, the options for the active configuration are displayed via a dropdown menu just below the file path.

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exploded configuration ironcad

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You can also select a configuration for an already placed view in the 2D drawing. Either by selecting the view and changing the configuration in the property manager (Drawing Browser) on the left side.

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exploded configuration ironcad

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Or right-click on a view and select Properties.

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exploded configuration 2d drawing ironcad

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BOM / Bill of Materials

When creating a Bill of Materials (BOM), the list of selectable configurations is displayed at the bottom left.

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usage configurations ironcad

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It is always a good idea to choose the Default configuration instead of No Configuration Selected, because the latter also shows suppressed objects but is always selected by default. The Default configuration is usually the one depicted in views and therefore the one the BOM is likely to reflect. If you have recurring issues with the BOM showing more than it should, this is usually the reason.

A BOM does not need to reflect what is shown in the drawing views. You can specify a different configuration for the BOM than the one used to depict the views. You can also change the configuration afterwards on an existing BOM. Right-click on the BOM and select Properties. At the top, there is then a dropdown menu with the configurations you can choose between.

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bomb configuration ironcad

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